What Is The Most Productive End Mill In Titanium?
Boeing experts recently responded to this question when it was submitted through our Aerospace Machining Zone
Personnel from Boeing's Research & Technology group recently answered readers' questions. One reader asked the following. To see the list of experts taking questions from readers right now, see our Ask An Expert page.
We are machining a 0.423-inch diameter Ti Beta C rod into a 0.375-inch hex. We use a 6-flute carbide end mill at a feed rate of 8.7 ipm and a 0.024-inch depth of cut. No finish pass is needed. We tried an insert cutter that went 3 times as fast, but the interrupted cut tended to tear the material. Can you recommend an end mill we can use for this job that will allow a much faster feed rate than we are now getting?
Response from Boeing’s Research & Technology group
For instances where we are taking very light radial cuts (0.050 inch or less), we use either 1-inch diameter 10-flute tools or 0.75-inch diameter 8-flute solid carbide end mills for finishing titanium parts. The key with these tools is never to touch a corner. We run them at 400 sfm with a 0.003-inch chip load. We go 46 to 48 ipm when cutting with the side of the tool.
If cutting with the bottom of the tool, back off to 300 sfm but maintain the 0.003-inch chip load. When cutting with the bottom of the tool, do not ramp to depth into a part, as there is not enough chip clearance. You should either create a start spot with a different tool, or start off of the part and feed onto it. Limit axial depth of cut to 0.030 inch, but feel free to maximize your step over. Full slots are possible in this situation.
Our primary experience is with titanium 6Al-4V, so your parameters may need to be adjusted for your material. We achieve 90+ minutes of tool life with these parameters as long as our radial engagement is 0.050 inch or less and we never touch a corner. You can buy cutters such as these from Fullerton, Data Flute, Robb Jack and Onsrud, among others. The cutters are a little bit expensive, but they run really fast and in most instances we find that the extra cost is more than worth it, because they are so productive they end up saving a lot of cost in the end.
Creating threaded holes in titanium alloys calls for proper techniques based on an understanding of both the properties of these materials and the peculiarities of the tapping process.
What’s it going to cost? How much space do I need? What environmental hassles will I encounter? How steep is the learning curve? Exactly what is anodizing? Here are answers to preliminary questions shops have about bringing anodizing in-house.
Simple process considerations can increase your productivity in milling titanium alloys.